In mechanical manufacturing, most dimensions on a drawing do not require their own tolerance. For these, there is the ISO 2768 standard, which establishes general tolerances by class and allows them to be controlled with a single indication on the title block. The result is cleaner drawings and less room for differing interpretations between the engineering office, the workshop, and quality control.
If you design parts or commission their manufacture, the ISO 2768 This is probably the most frequently used note on your drawings. Here's what it covers, the table of values per class, how to indicate it correctly, and what has changed, because the section on geometric tolerances is no longer valid.
What is ISO 2768?
It is an international standard for general tolerances: it defines how much a dimension can deviate when the drawing does not assign it an individual tolerance. It was published in 1989 in two parts:
- ISO 2768-1: Tolerances for linear and angular dimensions, with four classes: f, fine; m, medium; c, coarse; yv, very coarse.
- ISO 2768-2: General geometric tolerances, with three classes: H, K and L. This part is withdrawn and has been replaced by ISO 22081:2021.
In Spain, Part 1 is adopted as UNE-EN 22768-1:1994, identical to the ISO standard. It is intended for parts manufactured by machining or formed from sheet metal.
ISO 2768-1 General Tolerance Table
These are the permissible deviations for linear dimensions, in millimeters, according to the class indicated on the plan:
| Nominal size in mm | f · fine | m · media | c · thick | v · very thick |
|---|---|---|---|---|
| From 0.5 to 3 | ±0.05 | ±0.1 | ±0.2 | — |
| More than 3 to 6 | ±0.05 | ±0.1 | ±0.3 | ±0.5 |
| More than 6 to 30 | ±0.1 | ±0.2 | ±0.5 | ±1 |
| More than 30 to 120 | ±0.15 | ±0.3 | ±0.8 | ±1.5 |
| More than 120 to 400 | ±0.2 | ±0.5 | ±1.2 | ±2.5 |
| More than 400 to 1000 | ±0.3 | ±0.8 | ±2 | ±4 |
| More than 1000 to 2000 | ±0.5 | ±1.2 | ±3 | ±6 |
| More than 2000 to 4000 | — | ±2 | ±4 | ±8 |
For example, a 50 mm dimension in class m allows ±0.3 mm, meaning any measurement between 49.7 and 50.3 mm is valid. In class f, the margin is ±0.15 mm.
For outside radii and chamfer heights there is a separate table: ±0.2 mm up to 3 mm, ±0.5 mm from 3 to 6 mm and ±1 mm above in classes fy m. In classes cyv, these values are doubled.
Angular tolerances
The tolerance of the angles depends on the length of the shorter side:
| Shortest side in mm | fym | c | v |
|---|---|---|---|
| Up to 10 | ±1° | ±1°30′ | ±3° |
| More than 10 to 50 | ±0°30′ | ±1° | ±2° |
| More than 50 to 120 | ±0°20′ | ±0°30′ | ±1° |
| More than 120 to 400 | ±0°10′ | ±0°15′ | ±0°30′ |
| More than 400 | ±0°5′ | ±0°10′ | ±0°20′ |
Pay attention to dimensions less than 0.5 mm: the standard does not give them values, so the deviation must be indicated next to the dimension.
How to indicate ISO 2768 on a drawing
A simple note in or next to the title block, stating the standard and class, is sufficient. For example, «ISO 2768-m» applies the medium class to all linear and angular dimensions without their own tolerance.
Many drawings still bear «ISO 2768-mK», which combines the m class of part 1 with the K class of geometric tolerances of part 2. As that part is withdrawn, in new drawings it is advisable to define the general geometric tolerances according to ISO 22081 or to indicate them individually.
For the note to actually work, follow these steps:
- Define the function of each surface: what fits, what seals, what slides, and what serves as a reference.
- Choose the general class according to the process. The m class is the most common in machining and sheet metal work; reserve the f class for parts that really need it.
- Apply individual tolerances to critical dimensions, such as fits, bearing housings, or centering. Don't rely on the general specification.
- State the standard and class unambiguously. A «according to ISO» or an «ISO 2768» without a class is not sufficient.
- Check that the process and the measuring equipment can meet your requirements.
- Control plan revisions: if the class or standard changes, the workshop must work with the correct version.
What ISO 2768 does not cover
The overall grade doesn't solve everything. The following are excluded:
- Dimensions of less than 0.5 mm, which require their indicated tolerance.
- The auxiliary and theoretically exact dimensions.
- Geometric tolerances of shape, orientation and position, which are no longer governed by Part 2.
- Features with their own standard, such as welded constructions, have their general tolerances in ISO 13920.
If the part involves welding, bending, or forming, check which standard applies to each feature before finalizing the drawing.
General tolerances and quality control

A tolerance without a measurement method is a source of disputes. Before approving a part, define the references, the instrument, and the acceptance criteria. And keep measurement uncertainty in mind: a dimension may be within the acceptable range and still not be verifiable with the chosen equipment.
In the mass production, This translates into initial part studies, dimensional reports, and approval processes such as PPAP, which confirm that the process produces stably within tolerance.
What changes with the new edition of ISO 2768
ISO 2768-1:1989 remains valid, but ISO has a new edition dedicated to tolerance limits for linear and angular dimensions, scheduled for publication in June 2026, which will replace it. Part 2 is no longer in force: its replacement, ISO 22081:2021, is the current reference for general geometric tolerances.
The golden rule, meanwhile, is to indicate the standard on the drawing and, if your quality system requires it, the edition. This way, design, manufacturing, and the supplier all work with the same reference, and no one accepts or rejects a part based on a different version.
ISO 2768 in sheet metal parts and machining
In metallic transformed It is common for a single part to undergo laser cutting, bending, welding, and machining, and each process adds its own variation. In sheet metal, thickness, bending radius, and springback have an impact; in machining, clamping, the sequence of operations, and temperature are factors.
That's why it's a good idea to check the overall class with the manufacturer from the design stage, when changing it is inexpensive. It's what separates the engineering projects well-planned for those that get stuck in the workshop: functional tolerances where needed and general tolerances elsewhere.
Frequently Asked Questions
What does ISO 2768-mK mean on a drawing?
Linear and angular dimensions without their own tolerance follow class m of ISO 2768-1, and general geometric tolerances follow class K of ISO 2768-2. As that second part is withdrawn, it is advisable to check the indication on new drawings.
Which class of ISO 2768 is most commonly used?
In general-purpose machining and sheet metal work, class m is used. Class f is reserved for more demanding parts, and classes cyv are for rough parts, where more precision would increase the cost of the part without adding anything.
Does ISO 2768 replace individual tolerances?
No. It only covers dimensions without their own tolerance. Functional dimensions, such as fits or housings, must have their tolerance indicated on the drawing.
Conclusion
ISO 2768 simplifies drawings by establishing general tolerances for each class, but it doesn't replace functional analysis of the part. Choose the class according to the process, apply individual tolerances to critical dimensions, and review the guidelines inherited from the now-retired Part 2. And before each project, check which edition applies: the new version for linear and angular dimensions is already on its way.
Do you have a blueprint to manufacture?
At Toral, we manufacture parts in series and custom projects, starting with initial part studies and dimensional reports. Tell us what you need, and we'll advise you.
Ask us